Cut a straight transitional edge along a tagged path.
chamfer(
@solid: Solid,
length: number(Length),
tags: [Edge; 1+],
tag?: tag,
): Solid
Chamfer is similar in function and use to a fillet, except a fillet will blend the transition along an edge, rather than cut a sharp, straight transitional edge.
Arguments
| Name | Type | Description | Required |
|---|---|---|---|
solid | Solid | The solid whose edges should be chamfered | Yes |
length | number(Length) | The length of the chamfer | Yes |
tags | [Edge; 1+] | The paths you want to chamfer | Yes |
tag | tag | Create a new tag which refers to this chamfer | No |
Returns
Solid - A solid is a collection of extrude surfaces.
Examples
// Chamfer a mounting plate.
width = 20
length = 10
thickness = 1
chamferLength = 2
mountingPlateSketch = startSketchOn(XY)
|> startProfile(at = [-width/2, -length/2])
|> line(endAbsolute = [width/2, -length/2], tag = $edge1)
|> line(endAbsolute = [width/2, length/2], tag = $edge2)
|> line(endAbsolute = [-width/2, length/2], tag = $edge3)
|> close(tag = $edge4)
mountingPlate = extrude(mountingPlateSketch, length = thickness)
|> chamfer(
length = chamferLength,
tags = [
getNextAdjacentEdge(edge1),
getNextAdjacentEdge(edge2),
getNextAdjacentEdge(edge3),
getNextAdjacentEdge(edge4)
],
)
// Sketch on the face of a chamfer.
fn cube(pos, scale) {
sg = startSketchOn(XY)
|> startProfile(at = pos)
|> line(end = [0, scale])
|> line(end = [scale, 0])
|> line(end = [0, -scale])
return sg
}
part001 = cube(pos = [0,0], scale = 20)
|> close(tag = $line1)
|> extrude(length = 20)
// We tag the chamfer to reference it later.
|> chamfer(
length = 10,
tags = [getOppositeEdge(line1)],
tag = $chamfer1,
)
sketch001 = startSketchOn(part001, face = chamfer1)
|> startProfile(at = [10, 10])
|> line(end = [2, 0])
|> line(end = [0, 2])
|> line(end = [-2, 0])
|> line(endAbsolute = [profileStartX(%), profileStartY(%)])
|> close()
|> extrude(length = 10)
