A spool is a winding device for storing large batches of filament, wire, tape, etc

// Spool
// A spool is a winding device for storing large batches of filament, wire, tape, etc
// Categories: Manufacturing, Construction

// Set units
@settings(defaultLengthUnit = mm)

// Define shaft parameters
hubDiameter = 2in
spoolDiameter = 305
spoolThickness = 267
coreDiameter = 150
webThickness = 10
stockDiameter = 5

// Sketch the revolved profile of one side of the spool
spoolBase = startSketchOn(XY)
  |> startProfile(at = [0, coreDiameter / 2])
  |> xLine(length = spoolThickness / 2)
  |> yLine(endAbsolute = spoolDiameter / 2 - webThickness)
  |> tangentialArc(angle = -270deg, radius = webThickness)
  |> yLine(endAbsolute = hubDiameter / 2, tag = $seg01)
  |> xLine(endAbsolute = profileStartX())
  |> yLine(endAbsolute = profileStartY())
  |> close()
  |> revolve(axis = X)
  |> appearance(color = "#010101", metalness = 10, roughness = 70)

// Create a function that draws an indent on the outer faces of the spool
fn score(radius, length, depth) {
  scoreFn = startSketchOn(spoolBase, face = seg01)
    |> startProfile(at = [0, radius])
    |> arc(angleStart = 90deg, angleEnd = 55deg, radius = profileStartY(%))
    |> angledLine(angle = 55deg, length = length)
    |> arc(angleStart = 55deg, angleEnd = 90deg, radius = profileStartY(%) + length)
    |> line(endAbsolute = [profileStartX(%), profileStartY(%)])
    |> close()
    |> patternCircular2d(instances = 8, center = [0, 0])
    |> extrude(length = -depth)

  return scoreFn
}

// Circular pattern indents around each side face of the spool
scoreSketch01 = score(radius = hubDiameter / 2 + webThickness, length = (coreDiameter - hubDiameter) / 2 - (2 * webThickness), depth = spoolThickness / 2)
scoreSketch02 = score(radius = coreDiameter / 2, length = (spoolDiameter - coreDiameter) / 2 - (webThickness * 3), depth = webThickness / 2)
  // Mirror the spool base piece across the Y axis
  |> patternCircular3d(instances = 2, axis = [0, 1, 0], center = [0, 0, 0])

// Model a wound coil on the spool diameter
hel01 = helix(
  revolutions = spoolThickness / stockDiameter / 1.5,
  angleStart = 0deg,
  radius = (coreDiameter + stockDiameter) / 2,
  axis = X,
  length = spoolThickness,
)

// Sweep and color the coil
stock = startSketchOn(XZ)
  |> circle(center = [0, -(coreDiameter + stockDiameter) / 2], diameter = stockDiameter)
  |> sweep(path = hel01)
  |> translate(x = -spoolThickness / 2)
  |> appearance(color = "#f2471c", metalness = 70, roughness = 30)


Geometry Engine

Zoo CAD Engine Overview

KCL: A Programming Language for Parametric CAD

File Formats

A Practical Overview of CAD File Formats

Text-to-CAD

Text-to-CAD: Generating Editable, Parametric B-Rep CAD Models from Natural Language

Automation

Automating Your Workflow

spool