kcl →

startSketchOn

Start a new 2-dimensional sketch on a specific plane or face.

startSketchOn(data: SketchData, tag?: FaceTag) -> SketchSurface

Arguments

Name	Type	Description	Required
`data`	`SketchData`	Data for start sketch on. You can start a sketch on a plane or an solid.	Yes
`tag`	`FaceTag`	A tag for a face.	No

Returns

SketchSurface - A sketch type.

Examples

exampleSketch = startSketchOn("XY")
  |> startProfileAt([0, 0], %)
  |> line(end = [10, 0])
  |> line(end = [0, 10])
  |> line(end = [-10, 0])
  |> close()

example = extrude(exampleSketch, length = 5)

exampleSketch002 = startSketchOn(example, 'end')
  |> startProfileAt([1, 1], %)
  |> line(end = [8, 0])
  |> line(end = [0, 8])
  |> line(end = [-8, 0])
  |> close()

example002 = extrude(exampleSketch002, length = 5)

exampleSketch003 = startSketchOn(example002, 'end')
  |> startProfileAt([2, 2], %)
  |> line(end = [6, 0])
  |> line(end = [0, 6])
  |> line(end = [-6, 0])
  |> close()

example003 = extrude(exampleSketch003, length = 5)

Rendered example of startSketchOn 0

exampleSketch = startSketchOn("XY")
  |> startProfileAt([0, 0], %)
  |> line(end = [10, 0])
  |> line(end = [0, 10], tag = $sketchingFace)
  |> line(end = [-10, 0])
  |> close()

example = extrude(exampleSketch, length = 10)

exampleSketch002 = startSketchOn(example, sketchingFace)
  |> startProfileAt([1, 1], %)
  |> line(end = [8, 0])
  |> line(end = [0, 8])
  |> line(end = [-8, 0])
  |> close(tag = $sketchingFace002)

example002 = extrude(exampleSketch002, length = 10)

exampleSketch003 = startSketchOn(example002, sketchingFace002)
  |> startProfileAt([-8, 12], %)
  |> line(end = [0, 6])
  |> line(end = [6, 0])
  |> line(end = [0, -6])
  |> close()

example003 = extrude(exampleSketch003, length = 5)

Rendered example of startSketchOn 1

exampleSketch = startSketchOn('XY')
  |> startProfileAt([4, 12], %)
  |> line(end = [2, 0])
  |> line(end = [0, -6])
  |> line(end = [4, -6])
  |> line(end = [0, -6])
  |> line(end = [-3.75, -4.5])
  |> line(end = [0, -5.5])
  |> line(end = [-2, 0])
  |> close()

example = revolve({ axis = 'y', angle = 180 }, exampleSketch)

exampleSketch002 = startSketchOn(example, 'end')
  |> startProfileAt([4.5, -5], %)
  |> line(end = [0, 5])
  |> line(end = [5, 0])
  |> line(end = [0, -5])
  |> close()

example002 = extrude(exampleSketch002, length = 5)

Rendered example of startSketchOn 2

a1 = startSketchOn({
       plane = {
         origin = { x = 0, y = 0, z = 0 },
         xAxis = { x = 1, y = 0, z = 0 },
         yAxis = { x = 0, y = 1, z = 0 },
         zAxis = { x = 0, y = 0, z = 1 }
       }
     })
  |> startProfileAt([0, 0], %)
  |> line(end = [100.0, 0])
  |> yLine(-100.0, %)
  |> xLine(-100.0, %)
  |> yLine(100.0, %)
  |> close()
  |> extrude(length = 3.14)

Rendered example of startSketchOn 3