A manifold is a type of fitting that can be used to split or merge fluid flow in a system. Clamped tubes are typically refered to by their inner diameters, so the fittings are parameterized by their outer diameters

// Tube manifold
// A manifold is a type of fitting that can be used to split or merge fluid flow in a system. Clamped tubes are typically refered to by their inner diameters, so the fittings are parameterized by their outer diameters
// Categories: Automotive, Aerospace

// Set units
@settings(defaultLengthUnit = in)

// Define parameters
bodyDiameter = 5.8
portDiameter = 2.8
portCount = 4
portSpacing = 5
portHeight = 6
wallThickness = 0.2
beadDepth = 1
beadRadius = 0.2

// Model the interior hole of the manifold ports
hollowPort = startSketchOn(XY)
  |> circle(center = [0, 0], diameter = portDiameter - (2 * wallThickness))
  |> extrude(length = portHeight)

// Create the main body of the manifold and revolve
body = startSketchOn(XY)
  |> startProfile(at = [portHeight, bodyDiameter / 2])
  |> xLine(length = -beadDepth)

  // Add an SAE J1231 type 2 bead to seal a clamped tube connection
  |> arc(angleStart = 0deg, angleEnd = 180deg, radius = beadRadius)
  |> xLine(endAbsolute = -portCount * portSpacing)
  |> tangentialArc(angle = 90deg, radius = lastSegY())
  |> xLine(length = wallThickness)
  |> arc(angleStart = 180deg, angleEnd = 90deg, radius = bodyDiameter / 2 - wallThickness)
  |> xLine(endAbsolute = profileStartX())
  |> yLine(endAbsolute = profileStartY())
  |> close()
  |> revolve(axis = X)

  // subtract an instance of the hollow port feature at each port location
  |> subtract(tools =   clone(hollowPort)
    |> patternLinear3d(instances = portCount, distance = portSpacing, axis = [-1, 0, 0]))

// Trim the bottom of the ports so that they fit against the curved main body
bodyCut = startSketchOn(YZ)
  |> circle(center = [0, 0], diameter = bodyDiameter)
  |> extrude(length = -portCount * portSpacing, bidirectionalLength = 5)

// Model a revolved port at each location. Each should have a single beaded connection
ports = startSketchOn(YZ)
  |> startProfile(at = [0, portHeight])
  |> xLine(length = portDiameter / 2)
  |> yLine(length = -beadDepth)
  |> arc(angleStart = 90deg, angleEnd = -90deg, radius = beadRadius)
  |> yLine(endAbsolute = 0)
  |> xLine(endAbsolute = profileStartX())
  |> yLine(endAbsolute = profileStartY())
  |> close()
  |> revolve(axis = Y)
  |> subtract(tools = bodyCut)
  |> subtract(tools = hollowPort)
  |> patternLinear3d(instances = portCount, distance = portSpacing, axis = [-1, 0, 0])


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